unsectioned component in assembly [2001]

Hi,

Is it possible to lay out a sectioned view in a drawing leaving a given
component unsectioned [ I mean not cut, not just unhatched] , for
instance the battries in a torchlight.

Thanks

 

Sounds like you need a simplified rep, look it up in the help.

Geoff

 

You can either exclude components from being sectioned (it's in the section
properties menu) or increase the section line spacing so you can't see any
section lines in that component, which then just gives an outline of the
part.

 

I know this.
What I want is NOT to cut a given component in a section and see it
whole such as the battery and lamp but have the case sectioned. I've
seen drawings that do this, but not proeng.

 

It can be done as previously stated but it's mildly confusing. Suggest you
set up a couple of sectioned Iso (easy to see what's going on) views and
play with it a bit. I think the simplest way to go about it is to modify
the hatch (exclude or restore) in the drawing view then RMB on the sheet
and select Update Sheet. If you have more than one view based off of the
same XSEC, believe you'll have to do them individually (the changes are not
propogated to model XSEC). You can also work in the model (View Manager)
and subsequently placed views will conform to how ever you have the XSEC
configured. If you change XSEC in model you'll have to manually edit the
hatch and update existing views to get them to show the changes. Think
that's approx how it all works, anyway. 8~)

 

When you first set up a cross section, you have choices of what to section and the
kind of section and sectioning methods, including Planar, Offset and Zone. I think
you can accomplish NOT sectioning certain components with a Zone by creating a
quilt that encompasses the components you want to section, then selecting this as
your Zone definition. There are other methods of creating a zone by referencing
planes and component surfaces. There is some stuff in Assembly help on zones
pertaining to sectioning. It may be of some help, hopefully it won't be so big of
a struggle that you give up and just start erasing lines in the drawing. I'd like
to hear how the zone business works.

 

I think it's a bit poor that the component excluded from the section still
gets cut.

 

I've got hold of the wrong end of the stick then. I know everyone hates
binaries on NGs, so maybe if you could post the url of a picture like the
one you want to make I'd be able to help you?

 

it is indeed. Or did I miss something eventually?

"Exclude" does only exclude the part from hatching, not from the section.
How to display e. g. shafts in a sectioned gearbox - hatching excluded?

 

I haven't the means of posting this at the moment, but think of
batteries and a bulb in a torch sectioned down the middle, the effect is
like sectioning the body and hatching and overlaing the battery and bulb
in place. You will see the name on the battery and the full filament of
the bulb.

 

That really does sound like the 'exclude component' in the section
properties box. You need to update the view to see the full effect, until
then it just looks like an unhatched sectioned part.

 

To exclude items from being cut in a section view you have to control the
cutting plane. It is possible to do that with an offset section. In setup
of an offset section, you sketch the cutting plane profile (single line
thickness). Therefore you can sketch a plane profile that misses the items
you don't want cut. However there are a limitations to offset sections.
Both ends of the curve or chain of curves that makeup the cutting plane
profile must be straight lines. Also; according to PTC; Wildfire does not
"currently" have the capability to clip an offset section as it does with
regular "flat plane" sections in the new model sectioning tool. That means
you can only display the offset section views correctly as 2D orthographic
projections in a drawing.
If you want to generate a 3D shaded "cutaway style" view, I think you're
forced to actually cut the parts. I can think of a few ways to do that
depending upon needs. You could put the cut feature(s) in the respective
part model(s) on a common layer which could be used to suppress them when
not needed. That's probably the easiest way to do it.

 

Yes, John is quite right, if you exclude a component and then update the
view it reverts to it's full unsectioned state.