show stopper : "this drawing is more recent than the model"

Hi all,

when collaborating on a project using a shared directory on a server,
one person works on the assembly, another on a drawing of it.
The drafter saves the drawing and closes (and apparently also a new
version of the assembly file), the modeler save the assembly (not
touching the drawing file) and closes.

drafter re-opens the drawing and gets "this drawing is more recent than
the model" , plus all model-referencing items are either gone or invalid.

not very practical when a drawing and a model need to be created
consecutively.

Next test: modeller is not allowed to touch the main assembly... not
only impractical, but also counter-intuitive.

I had the drafter export and drop down to autocad to finish the drawings,
autocad

wzzl

 

With associative models and drawings this is unfortunately what you get. If
your drafter doesn't add drafting features to the objects being detailed,
then only the dimensions attatched to entities which move or are deleted
will fail.Careful planning of models can reduce these failures (put datum
curves and planes in the models quite early and dimension to those as they
are quite robust) but you'll never entirely escape them. Best practice seems
to be to have the modeller also do the detailing, as they understand the
design intent of the parts already, and can often find errors in their
models whilst detailing.
Some modellers may think this is 'beneath them' in which case I recommend
sacking them and hiring someone a little more customer oriented.

 

Are you guys using GD&T? If not, you could set the config option
'create_drawing_dims_only' to a value of 'yes' and part of your problem
would be eliminated. This works because your Driven(manually created)
dimensions would then get stored with the drawing files and not the
part/assy files. Therefore they wouldn't turn magenta-colored and have to be
re-created if the original model entities that they referenced are indeed
still intact; regardless of which part/assy model version your drawing
references. Such as when one user makes model modifications and places a
copy of their model in a folder that your detailer ends up referencing
whenever they retrieve the 2-D drawing file.

Hope this helps.

S.T.

 

: : > With associative models and drawings this is unfortunately what you get.
: If
: > your drafter doesn't add drafting features to the objects being detailed,
: > then only the dimensions attatched to entities which move or are deleted
: > will fail.Careful planning of models can reduce these failures (put datum
: > curves and planes in the models quite early and dimension to those as they
: > are quite robust) but you'll never entirely escape them. Best practice
: seems
: > to be to have the modeller also do the detailing, as they understand the
: > design intent of the parts already, and can often find errors in their
: > models whilst detailing.
: > Some modellers may think this is 'beneath them' in which case I recommend
: > sacking them and hiring someone a little more customer oriented.
: >
: >
: > : > > Hi all,
: > >
: > > when collaborating on a project using a shared directory on a server,
: > > one person works on the assembly, another on a drawing of it.
: > > The drafter saves the drawing and closes (and apparently also a new
: > > version of the assembly file), the modeler save the assembly (not
: > > touching the drawing file) and closes.
: > >
: > > drafter re-opens the drawing and gets "this drawing is more recent than
: > > the model" , plus all model-referencing items are either gone or
: invalid.
: > >
: > > not very practical when a drawing and a model need to be created
: > > consecutively.
: > >
: > > Next test: modeller is not allowed to touch the main assembly... not
: > > only impractical, but also counter-intuitive.
: > >
: > > I had the drafter export and drop down to autocad to finish the
: drawings,
: > > autocad
: > >
: > > wzzl
:
: Are you guys using GD&T? If not, you could set the config option
: 'create_drawing_dims_only' to a value of 'yes' and part of your problem
: would be eliminated. This works because your Driven(manually created)
: dimensions would then get stored with the drawing files and not the
: part/assy files. Therefore they wouldn't turn magenta-colored and have to be
: re-created if the original model entities that they referenced are indeed
: still intact; regardless of which part/assy model version your drawing
: references. Such as when one user makes model modifications and places a
: copy of their model in a folder that your detailer ends up referencing
: whenever they retrieve the 2-D drawing file.
:
You might also consider making the wall higher, which you appear to be trying to
erect anyway, by setting draw_models_read_only (another config.pro option) to yes
which prevents referencing the models. If your drafters can't store their changes
in the drawing model, those references can't be wiped out by a subsequent save
which, coming from the modellers, didn't contain those changes and won't contain
them the next time the drawing is opened. You really ought to be able to select
working scenarios and have software smart enough to pick options that make the
software behave to your benefit.

David Janes