Sheet Formats

Newbie from Proe platform trying to make some custom drawing formats with
title blocks. Previously in Pro we would have assigned within the parts and
assembly files paramaters or variables that contained the part/assembly
title, P/N, Originator, dates and etc.

This information would then pass thru into the drawing formats. All I seem
to find are notes for having the title blocks obtain info from the
properties dialog within the drawing file itself. I would not want to
duplicate efforts filling out the part, assembly and drawing variable values
increasing errors.

 

When you ar creating yor templates, put in a "dummy part" drawing view. Then
define your parameters using the custom properties from the "dummy part".
When you are finished, remove the drawing view and save the template. The
custom properties will remain.

Richard

 

Thanks for the info..

 

It sounds to me that you might be looking for some of the
functionality found in the plugin "custom properties manager", which
can be found on www.teamworks.dk . This program lets you import
information from the part and automatically insert it into your
drawing.

 

Sorry,

English & Lithuanian is all I can read & write.
I would still think this functionality is built within the box set.

 

You can do this with no add-ons.... There are, although, a few good
property input macros available, this one is very cool, I have modified
it for our needs and it has saved us much time:
http://www.rhapsodydesignsolutions.com/programs_1.html

When you create your drawing template, edit the sheet format insert a
blank note then right click and edit the properties. If you click on the
bottom button to the right of this dialog (picture of a link and a
hand), the next dialog will allow you to choose some pre-defined links
in either the current document (the drawing properties) or in the
current model on the sheet. Choose 'Model in view specified in sheet
properties' and get a property from the pull down list.

I have these properties (amongst others) on our sheet format:
$PRPSHEET:"SW-Folder Name"$PRPSHEET:"SW-File Name".SLDPRT
$PRPSHEET:"drw_number"
$PRP:"SW-Folder Name"$PRP:"SW-File Name".SLDDRW
$PRPSHEET:"vendor"
$PRPSHEET:"blank_length" x $PRPSHEET:"blank_width"
$PRPSHEET:"thick" MM
$PRPSHEET:"material"
$PRPSHEET:"parts_blank"
$PRPSHEET:"parts_unit"
$PRPSHEET:"finish"
$PRPSHEET:"weight" g
$PRPSHEET:"volume" mm³
$PRPSHEET:"surface" mm²
$PRPSHEET:"drawn"
$PRPSHEET:"checked"
$PRPSHEET:"drw_title"
$PRPSHEET:"prog_number"

These all pull the information from the part/assembly model, we have two
different templates that we use, one for parts, one for assemblies. You
can take and modify these to your needs, just make sure the properties
are in the part/assembly model and your drawing sheet will automatically
filled out from the model information.