Scaling and Configurations

I would like to create configurations for different sizes of a part. The
sizes are always uniform, therefore a simple scale feature would do the
trick. Does anyone know if there is a way to have different scaling factors
in a scale feature from configuration to configuration?

 

Wayne,

Good idea.... if it were a geometrically defined part.

Basically the part is nothing more than a model representation of a
customers logo. I took a JPEG of their logo a traced around it with a lot
of splines to create my extrudes. None of the sketches are fully defined
(or even partially for that matter). We will be using this logo on a
multitude of projects for this customer using different sizes here and
there. I wanted to simply have a config for each of the sizes.

Looks like zygzag's solution will work. I had already thought of this, but
I was hoping there was an easier way...

Thanks,

 

If you have to add scales many times I would suggest creating a simple
macro. Record the adding of a scale feature, you will get something like
this

Dim swApp As Object
Dim Part As Object
Dim boolstatus As Boolean
Dim longstatus As Long, longwarnings As Long
Dim FeatureData As Object
Dim Feature As Object
Dim Component As Object
Sub main()

Set swApp = Application.SldWorks

Set Part = swApp.ActiveDoc

'the first .5 is the X second Y third Z
Set Feature = Part.FeatureManager.InsertScale(0, True, 0.5, 0.5, 0.5)
'"50%" would be the new features name.
Part.SelectedFeatureProperties 0, 0, 0, 0, 0, 0, 0, 1, 0, "50%"
Part.ClearSelection2 True
Part.ClearSelection2 True

End Sub

This will add a centroid scale feature that would scale to 50% and be named
50% With a little more trouble you could add a user form, and a little bit
more the ability for it to create a new config.

To keep it simple
1)Create each new config while the default (assuming this is the unscaled
config) is active.
2)do not use derived configs(this way the new feature will be suppressed in
all other configs)