Repeat Regions

I need to know if it is possible in WF2 to create repeat regions that
will list all the PIECES in a PART.
The Company produces several models that are all similar with some of
the parts being different sizes in each model. The parts and assemblies
are created with Family tables.
It was decided to create the DRAWINGS using the DEFAULT assembly and
tables controlled with Repeat regions. These list the PART NAMES, PART
NUMBERS, QUANTITY etc. of all the parts in the ASSEMBLY with separate
tables below to list the differences between models.

Some of the PIECES that make up the PARTS themselves have dimensions
that are calculated with relations. Each of these dimensions has been
changed to a NAMED dimension.
Then each PART is created from the Default using Family tables and
given a PART NUMBER that is used in the Assembly drawings.

The problem is when I want to produce the PART drawings. It would be
nice to list each PIECE in a table (like with the Assembly)
automatically. But I have to enter each one manually, which is a pain,
especially if more pieces are added or piece names are changed.
But the main problem is that I need to have the varying dimensions
listed automatically by PART NUMBER, in a table below. Without this I
have to open each version of each part and get the required
measurements.

So to put it simply, I can't seem to create a repeat region for PARTS
(only for assemblies).
Second, I don't know how to access a NAMED dimension on a PIECE and
have it list the real dim associated to the PART NUMBER (in a table in
a PART drawing).

I really appreciate the help that you gave me previously and any
information that you can offer now.

Thanks
Peter

 

You can create such a table. It will be a table of parameters contained in a
family table. It's called a 2-D repeat region. There's a pretty good description
of how to set one up in detailing help under table repeat regions. Naturally, for
this to display what you want to see, the parameter, feature, dimension, etc.
needs to be listed as a column in the family table, so you might have to add some
columns.

 

David, thanks for the answer, the family table and repeat region worked
great.
However I still have part of the problem.
One of the dimensions is created with an equasion in RELATIONS while in
SKETCH mode.
This is on the generic model. To date there are 7 different size models
that use this generic in the family tables
The actual measurement of this part depends on the model chosen and the
dimension has been renamed to H01. I can't put the H01 dimension in the
family table because I don't know the correct dimension for each model.


What I need to know is: Is it possible to include this dimension (and
possibly others created with relations) in a table in a DRAWING so that
the table will display each instance of the part name in one column
with the correct H01 dimension in the column next to it?
And of course, how I go about doing it.

Thanks again
Peter.

 

Peter, you seem to thiink it's significant that ssome feature dimension is
created/governed in a sketch by a relation. It isn't really all that significant
where it originates: it's still a feature dimension. So, for example, you create a
relation in sketcher that says sd3=sd2*.7 and when you verify the relation and
complete the feature, the value of one part of a feature is checked by another
part of the same feature and is accessible only through the sketch. But, you'lll
notice, that when you finish the sketch, sd3 has turned into d3, a feature
dimension. So you change d3 to H01. When you create your family table, d3 or its
alias, H01, should be available as a dimension when you select the feature it is
attached to. And its value should update for every model where this value varies
as a result of the operation of the sketcher relation. Honestly, I'm mystified by
the problem. I've likely misunderstood something.

 

David, as usual it turns out to be something simple and stupid (on my
part).
When I added the named dimension (H01) to the Family table, I forgot to
VERIFY (how dumb).
So the dimension was shown correctly in the generic column and all
other models had an asterisk to say that they are all the same as the
original.
This was reflected in the drawing table that also displayed the the
same for each model.
Thanks for taking the time and effort to help solve the problem.

If I may, I have another question to ask. But this one probably doesn't
have a simple solution (if any at all).
I have created a PART which could be a simple weldment. It consists of
a front plate, a back plate, a side plate and a top plate.
As it is, I create a table with columns for ITEM#, NAME, DESCRIPTION,
MATERIAL and QUANTITY and rows for each piece. I must add the
information for each one manually.
Is there a way to add a table to the drawing that will automatically
list each of these pieces in the part, using the names in the MODEL
TREE?
Of course, I wouldn't want to include datums and holes etc.
I don't mind reading this information, if it is possible, but I have
read until my eyes bleed and I can't find what I need.
Do you know if this can be done and where I can get the info?

Thanks again
Peter

 

---------------

When I did weldments, they were not parts but assemblies. Each piece of the
weldment had a rough and finish size; cuts were made in the pieces to simulate
"squaring up" anything that needed preliminary machining. So, "cut" tables listed
both sizes and this was done with parameters equated to rough and finish sizes.
Your table doesn't seem to capture size information so I wonder what it's for.

If this were an assembly, these things would easily correspond to repeat region
parameters: rpt.index, asm.mem.name, asm.mem.cparam.description,
asm.mem.cparam.material, rpt.qty (cparam means "component parameter").
Other than this, it is possible to make a family table composed of features, to
pick features to include (which would seem to be all of them) and to include them
by their name. I have no idea what this buys you but, for what it's worth, it is
possible.

 

David, thanks very much for all the useful info and if you start to
feel good about 8:00 pm tonight, it is because I will be toasting to
your good health with a couple of beers.
And it probably won't do me any harm as well.

 

To your health and happiness! May fame and fortune follow! Cheers! And, forgive
me, I started without you (it's Friday and I'm Irish)