Random Parts being Hidden upon Drawing View Creation Sw2007

Just switched to 2007sp4, spent a day and a half baby sitting the
Conversion Wizard(14000 files), I have an assembly with ~600 parts
(created with sw2005) which when creating a new drawing some parts
become hidden. They're not hidden in the assembly or an any config they
just hide by themselves. I have to find them in the tree and select Show
Component. Anybody else seen this? Is there any solution other than
checking every part in every view?

Thanks
Whit

 

This is normal. In order to improve drawing performance SW will auto-
hide the parts it thinks will be hidden. However, doing something that
reveals the insides of an assembly will not unhide these parts. To do
that you need to go into properties for the view and unhide the parts.
This will also impact performance. But what good is performance if you
can't see the parts?

TOP

 

I was afraid of that, thank goodness my software is doing my thinking
for me, pretty soon a monkey really will be able to do my job. They've
been telling me that for years...

 

Does this sound like what you are seeing? This is an option under Tools,
Options, System Options, Drawings.

Automatically hide components on view creation. If selected, any components
of an assembly not visible in a new drawing view are hidden and listed on
the Hide/Show Components tab of the Drawing View Properties dialog box. The
components are present, and all component information is loaded. The
component names are transparent in the FeatureManager design tree.

WT

 

Dang that sounded promising, but it was unchecked. Some further
investigation revealed the parts that aren't showing in the first
assembly drawing don't show in some other assemblies, but they do show
in some others.

We have about 5 versions of a large assembly, the parts are not showing
in the two most recent assemblies, they do show in the third, but not
the fourth...weird.

Thanks

 

Also see large assembly mode, if on some parts will be hidden in
drawing views...seems like randomly chosen like Paul said before to
encrease performance.

// Krister

 

That did it, seems a shame to make one turn off a performance feature,
just to get an accurate drawing view.

I unchecked "Automatically hide components on view creation" and it
still hides parts "on the back" of the assembly, I can't figure out how
to show them without drilling down the feature tree. But at least I can
create a reasonably accurate view...

Thanks

 

As Wayne said, all hidden parts in a view are listed in in the
property dialoge box. Right klick in the view and take properties,
there are three flaps...go to "Hide/Show Components".....and the list
will show You all hidden parts. Just delete from the list and they
will be visible in the view again.

// Krister

 

Thanks again, the problem I was having is that when
selecting/right-click > DELETE a part to 'un-hide' nothing would happen.
I have to select the part in the list then press the delete key on the
keyboard to make *anything* happen... it seems to function properly with
that 'work-around'

Many thanks for the input...

....I need a refresher course.

Whit