problem encountered with model translation

Hi, all

When I converted the spectreS model file (35p.m, 35n.m) into spectre in
Cadence, I got the spectre model file (allModels.scs) smoothly. But the
Cadence called it stop due to a fatal error as I did spectre
simulation. It said that:

Simulating `input.scs' on mantle at 8:18:23 PM, Wed Apr 20, 2005.
Error found by spectre during circuit read-in.
"input.scs" 8: File `/MyLib/TSMC35/Models/allModels.scs'
does not contain any libraries.
"input.scs" 8: /MyLib/TSMC35/Models/allModels.scs: Error
found parsing the library file.
spectre terminated prematurely due to fatal error.

Can anyone figure out what caused the problem above? Thanks so much!

-Andy

 

If I remember right (spectreS is long ago for me)
in spectreS the models where single files for each
model whereas in spectre direct more than one model
is collected in a file, which has to contain one
ore more than one model library.

The file should look like this

simulator lang=spectre
library mymodellib

model nmos bsim3v3
....

endlibrary mymodellib



Maybe it is solves your issue if you put a
library and endlibrary statement in your *.scs file.


Bernd

 

I think this would only be an issue if you specify the model file and a
section in the model libraries form. If you specify the section name, the file
is expected to have library statements in it (as Bernd mentions in his post).
Without a specified section name, the file is included whole.

Regards,

Andrew.

 

Hi, Andrew

What you said can't be more right at this point. If I leave the section
option blank, spectre will like to play around the "allModels.scs"
file.

Thanks (also to Bernd)!

-Andy