Patterning split lines?

In simple words, can this be done?

Given that you can only create one closed split line profile per sketch and
you don't SEEM to be able to pattern the split line when it's created as a
feature. Is there any way this can be done? Any workarounds?

Thanks,

George.

 

Wow, yeah, that won't work. As for workarounds, you could try "pattern
faces", which might work depending on what you are doing. If you do a 0
offset of the split faces and pattern the surface body it might help.
It all depends on what you are trying to do with the new edges / faces.
If you are looking to make draft, that's tough. You might consider
cutting the part down to its smallest symmetrical form and patterning
bodies. You might also try to use extruded surfaces instead of
sketches, pattern the surfaces, make a big planar surface and do a
mutual trim with the extruded surfaces (to get a single surface body),
then do an intersection split line with the single surface body. Lots
of different things might work, it's hard to give you good advice
without knowing what you're trying to acheive.

matt

 

what I'm trying to do is split off some sections of a face to give it
different colour properties (in both SWX and PW) so it's not as if I'm doing
anything hugely complicated with it.... I guess I could break the part down
into a symmetrical unit and pattern the whole thing but this seems to me to
be a bit of a hatchet job.... looks like it may be the easiest way thoguh.

Odd.though... would have thought this would have been a pretty basic SWX
function.

 

I use split lines for this purpose quite often George. Unfortunately you are
correct, split lines can't be patterned. I have searched for a work around
for a while and I haven't found one. I search for ways to incorporate as
many face splits as possible using one closed sketch. It's like trying to
piece a puzzle together. It can be very frustrating.

 

Ahoy Georgy!

Aye, 'tis a bit of a pisser indeed. One note that may or may not be of
use to ye.... sometimes a cagy trick that's worked in the past be t'
draw a zig zagy line that runs off the surface then loops back like a
drunkin sailor with a shoddy map and compass. Thereby creatin' what
amounts t' seperate surfices through lacin ye sails with wild loops....

Arrrrrr

 

YARR! I get ye me hearty! That might be crazy enough to work... could
possibly get it all to work in one sketch.... still, it'll be a bit of a
pain in the rear to do, but it'll get me away I think.... still.. would be
nice if SWX could add pattern functionality to split lines.... it'd come in
dead handy sometimes!

 

Aye,

Cheers to that Matey...


Arrrrr

 

perhaps you can extrude the sketch as a surface, and then array this
surface. Create the split line with the intersection option with the
arrayed surfaces

 

You can use a Wrap. It allows you to have multiple profiles in the sketch.
Exit the sketch, then Insert/Feature/Wrap.

As I recall, Wrap only works on one face, but you can have multiple
profiles. Split Line works on multiple faces, but you can only have one
profile. Unless something has been added in SW06, there isn't an easy way to
have multiple profiles on multiple faces.

Jerry Steiger
Tripod Data Systems
"take the garbage out, dear"

 

well- if you have a surface (made form multiple profiles) that
intersects the target face/surface (made from multiple surfaces) then
the intersection option in the Split line feature allows you to create
split lines on the surface with multiple faces. Plus you can have
multiple disjoint faces allowed as well.

This is pretty much all I use these days as it seems a more robust
splitting tool.