Output SW drawing document to autocad.dwg or dxf

Why have the option to output to these formats in you can not be sure of the scale?
When I try to output to these formats, a message appears warning, that the dimensions may not be correct!! Huh?

 

Your Views in your drawings are probably scaled to fit the drawing sheet.
You get the choice to scale the sheet or scale the views. If you scale the
views the dimensions should be correct. If you scale the sheet then it's
questionable. Best thing to do is try it both ways and reopen the file back
into SW.

Regards,
Scott

Why have the option to output to these formats in you can not be sure of the
scale?
When I try to output to these formats, a message appears warning, that the
dimensions may not be correct!! H

 

My views are scaled, not the sheet, but I still get the warning box.
The dimensions may be correct, but why the warning box?
It introduces worries, as a lot of manufacturers still use AutoCAD.
Apart from checking every dimension for correctness, my only choice seems to
be, use AutoCAD, lol

 

The warning will also appear if you have any view in the drawing that is
scaled differently than the others. A detail view for example that is 3:1
when everything else is 1:1 will cause this.

It's really not too bad. One thing to watch out for is if you are exporting
a drawing with a title block that shows a scale factor (like 4:1) and you
check the scale 1:1 option when exporting a dwg. the dimensions of the parts
will be right but the title block scale factor will still obviously read
4:1. This can cause real confusion when you send it out.

If I'm exporting fabrication drawings (assuming they fit) I will make a D
sheet drawing at 1:1 scale and then export it.

Zander

 

Hi Pete -

This all makes sense. What it is is a "legal disclaimer" type of
thing.

Translated to english+AutoCADese it would say:

"since you have a few views that are scaled differently, and you have
different dimensions for them that have different DIMLFAC settings, be
careful when you add new dimensions in the output drawing as you might
need to adjust DIMLFAC based on the scale you chose to output with"



SMA

 

http://cax.idv.tw/forum/viewthread.php?tid=1379

 

"One thing to watch out for is if you are exporting a drawing with a title block that shows a scale factor (like 4:1) and you
check the scale 1:1 option when exporting a dwg. the dimensions of the parts will be right but the title block scale factor will still obviously read 4:1. This can cause real confusion when you send it out."

This is an excellent point, and something I hadn't thought about until seeing this. I just set up my templates with a scale factor. Instead of removing it, I wonder if there is another way to word it to help eliminate confusion? Something like "Print Scale 4:1"? Any ideas? Thanks,

Brian

 

Hi Brian,

If the exported drawing requires a title block AND needs to be exported 1:1
I will edit the title block scale factor to read 1:1 in autocad. Not very
elegant but...

Zander

"One thing to watch out for is if you are exporting a drawing with a title
block that shows a scale factor (like 4:1) and you
check the scale 1:1 option when exporting a dwg. the dimensions of the parts
will be right but the title block scale factor will still obviously read
4:1. This can cause real confusion when you send it out."

This is an excellent point, and something I hadn't thought about until
seeing this. I just set up my templates with a scale factor. Instead of
removing it, I wonder if there is another way to word it to help eliminate
confusion? Something like "Print Scale 4:1"? Any ideas? Thanks,

Brian

 

This is an excellent point, and something I hadn't thought about until

Eureka - You Got It - Print Size And Geometry Size Do Not Have To
Match.

Generally, Your end users will fall into two categories. People who
use data, in which case, the will have the geometry at 1:1 or those
who have a printed copy which will be scaled based on the paper size.
The "paper user" will need the 4:1 scale designator, the "cad person"
will not.

I have prepared at least 1000 2D prints (From acad & sw), maybe more
like 3000, and have never (yes never!) had a 2D DWG file with geometry
with a scale other than 1:1. This of course does not include detail
views which by definition are scaled differently. The only change I
ever made on a 4:1 print is to make the paper border (format) 1/4 the
size. This causes a fit print to be 4:1 scale, but the geometry is
invariable and always the "TRUE" 1:1 size.

(actually, I have cheated on this when I need to make a cheap metric
drawing of an inch part, but with poetic intent and the license that
accompanies it)

In fact, I would go as far as to say that anyone who intentionally
uses a GEOMETRY scale other than 1:1 on a 2d DWG, would in my mind be
absolutely insane and perhaps looking to make themselves intentionally
miserable. This means that might also often use DRAWING scales that
are 2:1,4;1, etc. so that the given geometry will fit the paper
correctly.

I have also done scores and scores of layouts for CNC and a hard and
fast rule to live by is to always always always use 1:1 and perhaps
even annotate it as such "ALL GEOMETRY TRUE SIZE", etc.

Simply put - geometry is always the true size, drawing scale is what
will change.

Later,

SMA

 

<<RANT>>
Just now using 2005 - they actually have implemented a WARNING that
your are outputing 1:1 geometry. LOFL. There should be a warning
when you do NOT! Silly ungrounded in reality stuff going on here.

When the hellp will we be able to output a multi-page DRW to series of
DXF/DWG files without all this manual labor? When will SW be smart
enough to open the file I just output in an external application? So
tired of this LABOR INTENSIVE poo poo just to output a DWG series.

<<RANT CONCLUDED>>

 

Oh boy are you in a good mood today....

Up late trying to get work done in time for the morning. Every action
taking another minute of precious pillow time away (including
complaining on google - hehe).

Thanks for the macro Dale! I just put you on my "Favorite People"
list.

Thanks a million. I will give it a whirl and let you know how it
goes.

Thanks,

Sean