Drawing Isometric view SHADED

Hello All,

I'm wondering if any one has any experience with using shaded ISO
views. I'm having a problem with the line thickness displayed and
plotted. I could not find any area for changing the thickness of ISO
Shaded views. Under document properties-line font, there are options
to change thickness of lines, however it doesn't seem to affect the
ISO view. Even if I change a standard projected view to shaded, and
then change the line thickness they change, but not the ISO view. Am
I missing something? I did call our VAR (creative design concepts)
and they suggested I send an email, which they can forward onto
Solidworks. I don't mind going this route, however I get the feeling
I will have better response this way. Any info is greatly
appreciated.

Regards,
Pete

 

Try this.

Click File>Print>Page Setup
Under Resolution and Scale, check High Quality

It will take a LOT longer to print (a major printing peeve of mine), but
should output good edge line thicknesses. When doing this however, if you
have any headers or footers on your document, they will not print (yes, yet
another printing peeve of mine).

 

I printed a lot of shaded ISO-views ....at least in SW 2004 without any
problems....haven't tried it 2005 yet due to the increasing plotting time.
On the other hand I don't pay that much attention to line thicknes in ISO
views as I do in the normal views....as long as it looks okay.

Krister L

 

Pete,
I print shaded ISO views often and I am not very happy with how SW2005
treats visible edges color.
Visible model edges in my regular views need to be red, but in ISO views I
need edges black. In SW2004 I used
Options-Colors, Drawings Visible Model Edges and set the color to red. It
used to affect regular views only, not the ISO views, which remained black.
SW2005 affects both!!! I have to put ISO views on separate sheet and change
print settings for these sheets. What a pain...

 

I have an idea. I don't use SW2005 yet so I don't know if it will work.

1. Create a layer with the color property set to black.
2. Right click on your iso view and select "Component Line Font". You may
have to click the arrows at the bottom of the menu to get this list item.
3. In the "Component Line Font" dialog, uncheck "Use document defaults".
4. Under Drawing view, check "From selection".
5. Then select the new layer your created in the layer box.

What happens? If this doesn't work immediately, try rebuilding. Did that
get it?
In SW2004, I can NOT get this to work like you would expect it to. But
since it sounds as though SW2005 works opposite than SW2004 for you, then it
just might work.

 

Pete,

Select the ISO view in your drawing and check to be sure that the "High quality" button is checked in the "Display
Style" box in the feature manager tree.

HTH,

M.T.

 

Seth,
I tried your suggestion - it works in 2005! The important thing is to
remember to check "From selection".
Now I don't have to print iso sheets separately. However, I didn't have to
do it in 2004.
On the brighter side, Pete, you can control line thickness in the same
Component Line Font dialog box.

 

zz,
Glad to hear it. You might be able to set up your templates with this new,
black layer, as well as a predefined iso view with this adjustment already
made in the Component Line Font dialog. This would prevent you from having
to go through this process on every new drawing.