Dimension a circle in section view

For years I've tried to figure this out, but haven't the slightest
idea if it is possible. If it is possible, how is it done?

See

http://www.dubea.org/dim_to_CL.gif

Currently I use multi-jog leader overlaid on itself to look like two
arrowheads. It's certainly not the cleanest solution in town and
rather difficult to get lined up.

Any ideas?

Any clever alternatives?

Thanks,

 

Perhaps a horizontal break in the view, add dimensions, then crop out
the top half?

It has yet to fail me (= "I haven't actually tried")

 

Tried it. It has failed me.

 

LOL!

Thanks I needed a good laugh.
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Chris

 

What I've done in the past is draw a construction line at the center
in the section view. Then I convert the edges that want to dimension.
Dimension these edges from the construction line; position the
dimension above the construction line to get the diameter dimension.

Drt

 

Not sure if this is what you want, but this is how I do it....
Create the detail view, but make the controlling circle big such that
both sides of the diameter can be seen in the detail view. Insert
diameter dimensions. The reduce the circle size such that the detail
now appears how you want it to, Rearrange dimensions to look pretty.

 

So I tried to post this twice but it never came through so here is my
final try...

You can do what you are wanting, search the help file for
Foreshortened Diameter for instructions. So far I have been unable to
find a way to add a double arrowhead to a dimension without that
dimension being a foreshortened diameter.

I would like to see solidworks add a double arrowhead to the list of
arrow heads that are presented when the user rmb on a dimension arrow
head. Doing that would allow the user to add a double arrowhead to any
dimension.

Sam

 

I would like to add that the Foreshortened Dimension only seems to
work if you have an Extrude. I went round and round with my VAR to
find out how to do this and we discovered it doesn't work on Revolved
Cuts. Keep it in mind. I'd like to see the double arrowhead added by
Solidworks also.

Jeff

 

create the DIA. dimensions in an unbroken view first. Then create
your detail view just like you show in the picture. Then just select
the DIA. dimension and HOLD DOWN the SHIFT key and drag and drop into
the detail view. You should see the DIA. dimension foreshortened. The
display option with double arrows can be controlled by your tools
"options" in document properties.

Don