Creating new parts

I use DBWorks today and make a new part based on an old one( where this is
preferred) with the "save as" command. Unfortunately do I only get the part,
it do not copy the linked drawing. So I have to make a new one.......

Is there a way to create a new part from an old part including the old
drawing? (In a simple way...)

I'll be most thankful to any comments on this one

Regards
Gunnar Storheim

 

Hi Gunnar

We use DBWorks and AFAIK there is no way to include the drawing when saving
a part/assembly.

The workaround that we use is to save the part/assembly first to the new
number (save as copy checked) then save the drawing to the new number.

Then in DBWorks highlight the drawing and you will see the original
part/assembly referenced. RMB on this part/assembly and select
"rename/replace>mark as document to be replaced."

Then select the new part/assembly which was created from the save as, and
RMB and select "rename/replace>mark as replacing document."

You will then see a dialogue box showing where the part/assembly is used.
You just select the new drawing that was created in the save as.

Hope this is clear enough and hope it helps.

FrankG

 

Hi Gunnar

I have the same problem with Smarteam. The work around I use and this
should also be the same for DBworks as it is a Solidworks routine
nothing to do with DBW or SMT.
Open the origonal drawing that is to be copied and do File SaveAs (do
not SaveAs copy) to your new number. The drawing on screen should now
have your new number showing on the title bar.
Right click on a drawing view and open the part or assembly (this will
be the part or assembly associated with the origonal drawing).
With the model active (do not close the new drawing) do a file SaveAs
(do not SaveAs copy), ignore the replace warning prompts.
Go back to your new drawing and it should be registering the new model
number.
No file hunting involved.

Regards

Brian

 

It's even easier. Open both the part and the drawing. Save the part with the
new name/location. It will give you a warning. Now save the drawing with its
new name/location.

Jerry Steiger
Tripod Data Systems

 

But it don't work with DBWorks.......

Gunnar Storheim
Seaproof Solutions

 

Gunnar,

I suspect you have the dataentr.lst option set on DBWorks save/saveas
option set.
This command overwrites the SW save and saveas function.
Turning this option off will allow SW to perform the required steps
needed to link your drawing using the steps illustrated by other
contributors.
When complete - turn on the dataentr.lst option. I would consider this
a batch process of legacy data.

Cheers,

Len K. Mar, PEng.
President
E-data Solutions